* NMOS Current Mirror SPICE .cir file
* Circuit description in netlist
* Commands and library link included

* To run on PSPICE 9.2 with EKV model parameters
* Friday, March 9, 2001
* Norbert Ulshoefer

* Open in PSPICE AD and watch outfile and/or probe window
*********************************************

** Settings **
* Default temperature is 27C
* .TEMP 125
* sets the nominal temperature to 105C

*********************************************
** Analysis setup **
* For more details look in the online manuals
* .STEP TEMP LIST 0 20 27 50 80 100 
*steps through different temperatures
.OP 
* .DC LIN Iin 100uA 100.001uA 0.001uA
* .tran 20ns 1000ns
.AC DEC 50 1 1700MEG
* .MC 500 DC ID(M2) YMAX OUTPUT ALL  
* .NOISE V(VDS2 0) V_Supply 20
*********************************************
** Library files **
* include model libraries of models you are using 
* library file must be in the same directory as .cir file
.lib EKVCMOS.lib
* also possible: .INC "EKVCMOS.lib" or .include EKVCMOS.lib

*********************************************
* Enter your circuit description here
* Schematics Netlist *

V_Supply    Vdd  0 3.3V
V_VDS2		VDS2 0 DC 0.9V
Iin 			Vdd  VGS DC 100uA AC 1uA
M1         	VGS  VGS 0 0 NMOS L=1um W=16um M=2 AD=14.4p AS=12p PD=9.8u PS=19u 
M2         	VDS2 VGS 0 0 NMOS L=1um W=16um M=4 AD=14.4p AS=12p PD=9.8u PS=19u 

********** end of circuit description 


* Call the probe to get your results displayed 
* for DC, AC, transient..... analysis
.probe
* end of simulation
.END